Tap Drill Size Calculator

Updated

Tap drill size calculator for UNC, UNF and metric cutting or forming taps, giving the drill for any thread percentage, its fit inside the 2B or 6H limits and a metric or inch swap.

Tap Size & Thread

Pick a tap; 75% thread is the usual chart target for cutting taps.

%
in
TPI
mm
mm
in
1/4-20 UNC Cutting Tap at 75% Thread
#7 Drill (0.2010 in)
Exact tap drill size 0.2013 in, the closest standard drill is under by 0.0003 in
75.4% Thread Engagement
One Size Larger13/64 in · 72.2%
One Size Smaller#8 · 78.5%
Go one size larger in stainless or deep blind holes to cut tapping torque, and one smaller in soft metal that needs more grip.
5.1 mm Metric Drill Equivalent
Thread % with 5.1 mm75.8%
Exact Size in mm5.113 mm
The closest metric drill to the exact size, for a shop that only stocks metric bits. Its thread % is shown on the left.
#1 Drill for a Forming Tap
Forming Thread %64.7%
Exact Forming Size0.2279 in
Forming taps push metal instead of cutting it, so they need a larger hole sized for about 65% thread.
45% Up the 2B Minor Band
Min Minor Diameter0.1959 in
Max Minor Diameter0.2074 in
A cutting tap leaves the drilled hole as the thread minor diameter, so the drill should fall inside the 2B limits.
Thread & Drill Section Diagram75.4% thread
Drill 0.2010 inMajor 0.2500 in2B minor 0.1959 in to 0.2074 in75.4% thread (cutting)Hole axis, half sectionThread depth 0.0245 in per side of 0.0325 in at 100%
Drill Options Around This Tap9 drills
DrillDiametermmThread %2B Minor
#110.1910 in4.851 mm90.8%Under min
#100.1935 in4.915 mm87.0%Under min
#90.1960 in4.978 mm83.1%Inside
#80.1990 in5.055 mm78.5%Inside
#70.2010 in5.105 mm75.4%Inside
13/64 in0.2031 in5.159 mm72.2%Inside
#60.2040 in5.182 mm70.8%Inside
#50.2055 in5.220 mm68.5%Inside
#40.2090 in5.309 mm63.1%Over max
UNC Tap Drill ChartUNC chart
TapCutting at 75%Forming at 65%2B MinorMetric Option
#1-64#53 · 67%#51 · 56%0.0561-0.06361.45 mm
#2-56#50 · 69%5/64 in · 65%0.0667-0.07431.75 mm
#3-48#47 · 76%#43 · 71%0.0764-0.08452 mm
#4-40#43 · 71%#38 · 62%0.0849-0.09392.25 mm
#5-40#38 · 72%#33 · 71%0.0979-0.10622.55 mm
#6-32#36 · 78%1/8 in · 61%0.1042-0.11392.75 mm
#8-32#29 · 69%#25 · 68%0.1302-0.13883.4 mm
#10-24#25 · 75%11/64 in · 64%0.1449-0.15553.8 mm
#12-24#16 · 72%#8 · 60%0.1709-0.18074.5 mm
1/4-20#7 · 75%#1 · 65%0.1959-0.20745.1 mm
5/16-18F · 77%L · 60%0.2524-0.26506.6 mm
3/8-165/16 in · 77%S · 64%0.3073-0.32148 mm
7/16-14U · 75%13/32 in · 64%0.3602-0.37609.3 mm
1/2-1327/64 in · 78%15/32 in · 60%0.4167-0.433610.8 mm
9/16-1231/64 in · 72%17/32 in · 55%0.4723-0.490312.2 mm
5/8-1117/32 in · 79%37/64 in · 76%0.5266-0.546013.5 mm
3/4-1021/32 in · 72%45/64 in · 69%0.6417-0.662716.5 mm
7/8-949/64 in · 76%53/64 in · 62%0.7547-0.777619.5 mm
1-87/8 in · 77%15/16 in · 74%0.8647-0.889722.5 mm
1-1/8-763/64 in · 76%1 1/16 in · 64%0.9704-0.997925 mm
1-1/4-71 7/64 in · 76%1 3/16 in · 64%1.0954-1.122928 mm
1-3/8-61 7/32 in · 72%1 19/64 in · 69%1.1946-1.225131 mm
1-1/2-61 11/32 in · 72%1 27/64 in · 69%1.3196-1.350134 mm
Taps a #7 Drill Fits2 taps
Tap That FitsThread %Minor Check
1/4-20 UNC75.4%Inside
M6 × 168.9%Inside
Step-by-Step Tap Drill Math7 steps
Thread1/4-20 UNC: D = 0.2500 in, P = 1 ÷ 20 = 0.0500 in
Exact drilld = D - 0.01299 × % × P = 0.2500 - 0.01299 × 75 × 0.0500 = 0.2013 in
Closest drill#7 = 0.2010 in, 0.0003 in under exact
Thread %% = (D - d) ÷ (0.01299 × P) = (0.2500 - 0.2010) ÷ (0.01299 × 0.0500) = 75.4%
Thread depth(D - d) ÷ 2 = 0.0245 in per side; 100% = 0.01299 × 100 × P ÷ 2 = 0.0325 in
2B minorD1 min = D - 1.082532 × P = 0.1959 in; tolerance = 0.25P - 0.4P² = 0.0115 in → D1 max = 0.2074 in
Forming tapd = D - 0.0068 × 65 × P = 0.2279 in → #1 = 0.2280 in (64.7%)
Drill #7, Then Tap 1/4-20 UNC
The hole sits inside the 2B minor limits. In tough metals or deep blind holes, 13/64 in (72.2%) lowers tapping torque.

Tap Drill Size Calculator Drills for Inch Threads

A 1/4-20 UNC tap takes a #7 drill (0.2010 in), which leaves 75.4% thread. A 3/8-16 takes 5/16 in at 77.0%, and a 1/2-13 takes 27/64 in at 78.2%.

Each row below is a tap drill size calculator result for a cutting tap at 75% thread. The 2B column is the allowed minor diameter of the finished hole, and the last column is the closest metric drill for shops that stock only metric bits.

UNC TapExact at 75%DrillThread %2B Minor (in)Metric Drill
#4-400.0876 in#4370.8%0.0849-0.09392.25 mm
#6-320.1076 in#3677.6%0.1042-0.11392.75 mm
#8-320.1336 in#2969.0%0.1302-0.13883.4 mm
#10-240.1494 in#2574.8%0.1449-0.15553.8 mm
#12-240.1754 in#1672.1%0.1709-0.18074.5 mm
1/4-200.2013 in#775.4%0.1959-0.20745.1 mm
5/16-180.2584 inF76.9%0.2524-0.26506.6 mm
3/8-160.3141 in5/16 in77.0%0.3073-0.32148 mm
7/16-140.3679 inU74.9%0.3602-0.37609.3 mm
1/2-130.4251 in27/64 in78.2%0.4167-0.433610.8 mm
9/16-120.4813 in31/64 in72.2%0.4723-0.490312.2 mm
5/8-110.5364 in17/32 in79.4%0.5266-0.546013.5 mm
3/4-100.6526 in21/32 in72.2%0.6417-0.662716.5 mm
7/8-90.7668 in49/64 in75.8%0.7547-0.777619.5 mm
1-80.8782 in7/8 in77.0%0.8647-0.889722.5 mm

Fine threads have shallower teeth, so their tap drill size calculator results sit closer to the tap size. A 1/4-28 UNF takes a #3 drill at 79.8%, while the coarse 1/4-20 takes the smaller #7.

UNF TapExact at 75%DrillThread %2B Minor (in)Metric Drill
#6-400.1136 in#3377.0%0.1109-0.11862.9 mm
#8-360.1369 in#2977.6%0.1339-0.14163.5 mm
#10-320.1596 in#2176.4%0.1562-0.16414.1 mm
#12-280.1812 in#1473.3%0.1773-0.18574.6 mm
1/4-280.2152 in#379.8%0.2113-0.21985.5 mm
5/16-240.2719 inI74.8%0.2674-0.27716.9 mm
3/8-240.3344 inQ79.4%0.3299-0.33968.5 mm
7/16-200.3888 in25/64 in72.2%0.3834-0.39499.9 mm
1/2-200.4513 in29/64 in72.2%0.4459-0.457411.5 mm
9/16-180.5084 in33/64 in65.0%0.5024-0.515012.9 mm
5/8-180.5709 in37/64 in65.0%0.5649-0.577514.5 mm
3/4-160.6891 in11/16 in77.0%0.6823-0.696417.5 mm
7/8-140.8054 in13/16 in67.4%0.7977-0.813520.5 mm
1-120.9188 in59/64 in72.2%0.9098-0.927823.5 mm

Most tap drill size calculator drills in these tables match the standard drill and tap size chart. The two 65% rows are the exception, because their chart drills land just outside the class limits of those threads.

Number and letter drills fill the gaps between fractional sizes, so a tap drill size calculator in inches can land within a thousandth of the exact hole. Fractional-only sets jump 1/64 in, or 0.0156 in, at a time.

Metric Tap Drill Chart and the D - P Rule

A metric coarse tap drill is the major diameter minus the pitch. An M6 × 1 takes a 5 mm drill, an M8 × 1.25 takes 6.8 mm, and an M10 × 1.5 takes 8.5 mm.

That rule gives 77% thread every time, since one pitch is 77% of the 1.299 P full-thread depth. A metric tap drill size calculator at 75% lands on the same drill for most sizes and splits off only near a rounding line.

Metric Coarse TapChart Drill (D - P)Thread %Drill at 75%6H Minor (mm)Forming Drill
M3 × 0.52.5 mm77.0%2.5 mm2.459-2.5992.8 mm
M4 × 0.73.3 mm77.0%3.3 mm3.242-3.4223.7 mm
M5 × 0.84.2 mm77.0%4.2 mm4.134-4.3344.6 mm
M6 × 15 mm77.0%5 mm4.917-5.1535.6 mm
M8 × 1.256.8 mm73.9%6.8 mm6.647-6.9127.4 mm
M10 × 1.58.5 mm77.0%8.5 mm8.376-8.6769.3 mm
M12 × 1.7510.2 mm79.2%10.3 mm10.106-10.44111.2 mm
M14 × 212 mm77.0%12.1 mm11.835-12.21013 mm
M16 × 214 mm77.0%14 mm13.835-14.21015 mm
M20 × 2.517.5 mm77.0%17.5 mm17.294-17.74419 mm
M24 × 321 mm77.0%21 mm20.752-21.25222.5 mm

A 12 mm coarse tap is the one size where charts and a tap drill size calculator part ways, by one 0.1 mm drill step.

M12 × 1.75 minus its pitch is 10.25 mm, and charts list 10.2 mm at 79.2% thread. A 10.3 mm drill gives 74.8%, and both sit inside the 6H limits of 10.106 to 10.441 mm.

Fine pitches follow the same rule with a smaller pitch. A tap drill size calculator in mm lands on these drills for common fine threads.

Metric Fine TapChart DrillThread %6H Minor (mm)Forming Drill
M8 × 17 mm77.0%6.917-7.1537.6 mm
M10 × 1.258.8 mm73.9%8.647-8.9129.4 mm
M12 × 1.510.5 mm77.0%10.376-10.67611.3 mm
M12 × 1.2510.8 mm73.9%10.647-10.91211.4 mm
M16 × 1.514.5 mm77.0%14.376-14.67615.5 mm

An M12 × 1.5 fine tap therefore takes a 10.5 mm drill, not the 10.2 mm drill of the coarse thread. A 10.2 mm hole would leave 92.4% thread in M12 × 1.5, below its 10.376 mm minimum minor diameter.

Formula for Tap Drill Size and Thread Percent

The drill in every tap drill size calculator formula equals the major diameter minus 0.01299 times the thread percentage times the pitch. For a 1/4-20 at 75%, that is 0.25 - 0.01299 × 75 × 0.05 = 0.2013 in.

Here d is the drill diameter, D is the tap's major diameter, T is the thread percentage and P is the pitch. For inch taps P is 1 ÷ TPI in inches; for metric taps P is the pitch in mm and d comes out in mm.

Inch and metric work share one constant, so a tap drill size calculator in inches and one in mm give the same thread depth for the same pitch.

The 0.01299 constant is 1.299 ÷ 100. A 100% thread is 0.6495 P deep on each side, three quarters of the sharp 60° V, so the full depth across the hole is 1.299 P.

FM Carbide's tapping formulas use the same 0.01299 per TPI, written as pitch ÷ 76.98 for metric, so a tap drill size calculator built on them agrees to the thousandth.

The reverse form gives the thread percentage from a drill already in the rack. A #7 drill at 0.2010 in in a 1/4-20 gives (0.25 - 0.2010) ÷ (0.01299 × 0.05) = 75.4%.

Thread depth follows from the same numbers. That #7 hole leaves 0.0245 in of thread on each side, out of 0.0325 in for a full 100% thread, and every tap drill size calculator figure traces back to this one line of math.

Forming Taps Need a Bigger Hole

A forming tap needs a hole near 65% thread on a constant of 0.0068, so a 1/4-20 forming tap takes a #1 drill (0.2280 in) instead of the #7 used for cutting.

The symbols match the cutting formula, with T set near 65%. Machinery's Handbook and FM Carbide both use 0.0068 per TPI, or pitch ÷ 147.06 for metric, and recommend 60 to 65% for forming taps in steel and ductile alloys.

TapCutting DrillForming Exact at 65%Forming DrillForming Thread %
#10-24 UNC#250.1716 in11/64 in64.0%
1/4-20 UNC#70.2279 in#164.7%
3/8-16 UNC5/16 in0.3474 inS63.5%
1/2-13 UNC27/64 in0.4660 in15/32 in59.7%
M6 × 15 mm5.558 mm5.6 mm58.8%
M8 × 1.256.8 mm7.447 mm7.4 mm70.6%
M10 × 1.58.5 mm9.337 mm9.3 mm68.6%
M12 × 1.7510.2 mm11.226 mm11.2 mm67.2%

Using a cutting tap drill size calculator result with a forming tap is the classic way to snap one. A #7 hole in a 1/4-20 forming tap works out to 144% forming thread, so the tap has far more metal to push than it is built for.

Some published forming formulas divide by 294.12 instead of 147.06, which halves the depth and pushes a tap drill size calculator result too large.

That version puts an M6 forming hole at 5.78 mm instead of 5.56 mm, and a 1/4-20 hole at 0.2390 in instead of 0.2279 in, so the formed thread comes out shallow.

A forming tap squeezes metal inward, so the finished minor diameter ends up smaller than the drilled hole. Check formed threads with a go/no-go gauge rather than by measuring the hole.

Class 2B and 6H Minor Limits

A cutting tap leaves the drilled hole as the thread's minor diameter, so the drill must fall between the class limits. For a 1/4-20 UNC 2B thread that window is 0.1959 to 0.2074 in, or 83.3% down to 65.6% thread.

D1,min is the basic minor diameter, which works out to 83.3% thread on every size. Any drill smaller than that forces the tap to cut the crest too, which raises torque and breaks small taps.

The upper limit adds a tolerance to that minimum. ASME B1.1 sets the 2B tolerance at 0.25 P - 0.4 P² for 1/4 in and larger, and at 0.05 P2/3 + 0.03 P ÷ D - 0.002 below 1/4 in.

ISO 965-1 sets the metric 6H tolerance, 0.236 mm for a 1 mm pitch and 0.300 mm for 1.5 mm, and those widths set the 6H window in any tap drill size calculator check.

Those limits catch a case the usual chart and a nearest-drill tap drill size calculator both miss, on two fine inch threads.

For 9/16-18 UNF, 33/64 in is 0.0006 in over the 0.5150 in maximum, while 1/2 in is under the 0.5024 in minimum. No inch drill fits, but a 12.9 mm drill gives 75.7% and sits inside.

The 5/8-18 UNF works the same way. Its chart drill of 37/64 in runs over the 0.5775 in limit and 9/16 in falls under 0.5649 in, while a 14.5 mm drill gives 75.0% and fits the class.

Coarse threads leave room in both directions. A 1/2-13 2B hole runs from Z at 87.1%, which is under the minimum, to 7/16 in at 62.5%, which is over the maximum, so 27/64 in is the only inch drill that fits.

Picking Thread Percentage for the Job

Use 75% thread for most cutting taps, 60 to 70% for stainless, hard alloys and deep blind holes, and up to about 80% in soft metal that needs grip.

FM Carbide puts the cutting range at 65 to 75%, so the usual 75% chart target sits at the top of that band.

Moving one drill size changes the thread by 1.4 to 4.6 points on a 1/4-20. Every drill below stays inside the 2B window except #10, so the decision is torque versus grip rather than fit.

Drill for 1/4-20DiameterThread %2B Minor Check
#100.1935 in87.0%Under minimum
#90.1960 in83.1%Inside
#80.1990 in78.5%Inside
#70.2010 in75.4%Inside
13/64 in0.2031 in72.2%Inside
#60.2040 in70.8%Inside
#50.2055 in68.5%Inside

Metric steps are bigger in a tap drill size calculator in mm, since drills move in 0.1 mm. For M8 × 1.25, a 6.7 mm drill gives 80.1%, 6.8 mm gives 73.9% and 6.9 mm gives 67.7%, all inside 6H, while 7 mm drops to 61.6% and fails the limit.

Thread percentage past 75% adds torque and tap wear for strength the joint seldom uses. When a bolt must carry its full load, longer engagement does more than a tighter hole, and the Bolt Pull Out Force Calculator sizes that length.

One Drill, Several Taps

An 8 mm drill taps a 3/8-16 UNC at 74.0% thread, and a 12 mm drill taps an M14 × 2 at 77.0%, both inside their class limits.

Many drills in the rack serve both an inch and a metric thread, and the thread percent each pairing gets in a tap drill size calculator result decides whether it fits the class.

DrillTaps It Fits (Cutting)Thread %Class Check
#29 (0.1360 in)#8-32 UNC / #8-36 UNF69.0% / 77.6%Both inside
5 mmM6 × 1 / 1/4-20 UNC77.0% / 81.8%Both inside
#7 (0.2010 in)1/4-20 UNC / M6 × 175.4% / 68.9%Both inside
6.8 mmM8 × 1.25 / 5/16-24 UNF73.9% / 82.7%Both inside
8 mm3/8-16 UNC74.0%Inside
8.5 mmM10 × 1.5 / 3/8-24 UNF77.0% / 74.6%Both inside
10.2 mmM12 × 1.75 / 7/16-28 UNEF79.2% / 77.4%Both inside
12 mmM14 × 2 / 9/16-12 UNC77.0% / 83.2%Both inside

A 6.8 mm drill also sits close to 5/16-18, but there it gives only 62.1% thread and runs over the 2B maximum. Use F for that tap, since closeness in size alone does not mean the hole fits.

The same check answers a common question in reverse. An 8 mm hole is not for an M8 tap at all, since an M8 × 1.25 needs 6.8 mm. An M8 bolt passing through a part needs a clearance hole sized with the Clearance Hole Calculator.

Sizing Taps, Checking Drills and Reading Markings

Shop shorthand causes most tap mix-ups, since a 1/4-20 and an M6 × 1 differ by only 0.35 mm in diameter and a #7 and #8 drill by 0.002 in.

What is a tap drill size?

A tap drill size is the diameter of the hole drilled before tapping, sized so the tap leaves a set share of thread. For 1/4-20 UNC it is #7 (0.2010 in), and for M6 × 1 it is 5 mm.

The hole size decides thread depth, tap torque and whether the thread passes its class gauge. Reading a tap drill size calculator result as drill, thread percentage and class limits lets both strength and fit be judged before drilling.

How to check drill size?

Read the size stamped on the shank, then measure across the margins near the point with a micrometer or calipers, not across the flutes. A #7 drill should read 0.2010 in and a 6.8 mm drill 0.2677 in.

A drill gauge plate sorts loose number and letter drills fast, which matters when neighbors differ by a few thousandths of an inch.

FM Carbide notes that drill wear and runout can shift the real hole size, so check a test hole on critical threads before trusting any tap drill size calculator figure.

How to identify tap size?

Read the marking on the tap shank first, such as 1/4-20 NC or M6 × 1 6H. If the marking is worn, measure the major diameter across the thread crests and check the pitch with a thread gauge.

Several inch and metric taps sit close together, so both numbers matter before any tap drill size calculator lookup. The Thread Calculator lists full dimensions for any size found.

Inch TapDiameterPitchClose Metric TapDiameterPitch
#10-244.83 mm1.058 mmM5 × 0.85 mm0.8 mm
1/4-206.35 mm1.270 mmM6 × 16 mm1.0 mm
5/16-187.94 mm1.411 mmM8 × 1.258 mm1.25 mm
3/8-169.53 mm1.588 mmM10 × 1.510 mm1.5 mm

A 5/16-18 and an M8 × 1.25 differ by only 0.06 mm in diameter, so pitch is the reliable tell. Over 25.4 mm of thread, the inch tap shows 18 crests and the metric tap about 20.3.

How many drills do I need per tap?

One drill per tap size serves the whole taper, plug and bottoming set, because all three cut the same thread and share one tap drill size calculator answer. A 1/4-20 set needs only a #7 drill.

A forming tap of the same size needs its own, larger drill: #1 for 1/4-20 and 5.6 mm for M6 × 1. A countersink or chamfer at the hole mouth helps the tap start, and the Countersink Depth Calculator sets its depth.