Bend allowance calculator for sheet, tube and bar, with bend deduction, outside setback, flat blank length, the bend line marks, and a K-factor from DIN 6935 or from one test bend.
Enter thickness, inside radius, bend angle and K-factor; flanges give the flat blank.
Angle Type, K Source & Flanges
Bend Section Diagram
Bend Allowance Chart by Angle
| Bend Angle | Included | Bend Allowance | Outside Setback | Bend Deduction |
|---|---|---|---|---|
| 15° | 165° | 0.0226 in | 0.0158 in | 0.0090 in |
| 30° | 150° | 0.0452 in | 0.0322 in | 0.0191 in |
| 45° | 135° | 0.0679 in | 0.0497 in | 0.0316 in |
| 60° | 120° | 0.0905 in | 0.0693 in | 0.0481 in |
| 90° | 90° | 0.1357 in | 0.1200 in | 0.1043 in |
| 120° | 60° | 0.1810 in | 0.2078 in | 0.2347 in |
| 135° | 45° | 0.2036 in | 0.2897 in | 0.3758 in |
| 150° | 30° | 0.2262 in | 0.4478 in | 0.6695 in |
90° Bend Allowance Chart by Radius
| Inside Radius | R/T | DIN 6935 K | 90° Bend Allowance | 90° Bend Deduction |
|---|---|---|---|---|
| 0.0300 in | 0.5 | 0.250 | 0.0707 in | 0.1093 in |
| 0.0600 in | 1 | 0.325 | 0.1249 in | 0.1151 in |
| 0.0900 in | 1.5 | 0.369 | 0.1762 in | 0.1238 in |
| 0.1200 in | 2 | 0.400 | 0.2262 in | 0.1338 in |
| 0.1800 in | 3 | 0.444 | 0.3246 in | 0.1554 in |
| 0.2400 in | 4 | 0.476 | 0.4218 in | 0.1782 in |
| 0.3000 in | 5 | 0.500 | 0.5184 in | 0.2016 in |
Step-by-Step Bend Allowance Math
Bend Allowance Calculator Chart for 90° Bends
A 90° bend in 0.060 in sheet with a 0.060 in inside radius and a K-factor of 0.44 uses 0.1357 in of bend allowance. Its bend deduction is 0.1043 in, so 3 in and 2 in outside flanges need a 4.8957 in flat blank.
The chart below holds the inside radius equal to the thickness, the most common press brake setup. Each row is a bend allowance calculator result at K 0.44 beside the DIN 6935 K of 0.325 for the same R/T of 1.
| Thickness | BA at K 0.44 | Outside Setback | BD at K 0.44 | BA at DIN K 0.325 | BD at DIN K 0.325 |
|---|---|---|---|---|---|
| 0.030 in | 0.0679 in | 0.0600 in | 0.0521 in | 0.0624 in | 0.0576 in |
| 0.048 in | 0.1086 in | 0.0960 in | 0.0834 in | 0.0999 in | 0.0921 in |
| 0.0598 in (16 ga) | 0.1353 in | 0.1196 in | 0.1039 in | 0.1245 in | 0.1147 in |
| 0.090 in | 0.2036 in | 0.1800 in | 0.1564 in | 0.1873 in | 0.1727 in |
| 0.125 in | 0.2827 in | 0.2500 in | 0.2173 in | 0.2602 in | 0.2398 in |
| 0.1875 in | 0.4241 in | 0.3750 in | 0.3259 in | 0.3902 in | 0.3598 in |
| 0.250 in | 0.5655 in | 0.5000 in | 0.4345 in | 0.5203 in | 0.4797 in |
Metric sheet scales the same way, because every term grows with thickness when R equals T. These metric 90° values use the same two K-factors as the inch chart.
| Thickness | BA at K 0.44 | Outside Setback | BD at K 0.44 | BA at DIN K 0.325 | BD at DIN K 0.325 |
|---|---|---|---|---|---|
| 1 mm | 2.262 mm | 2.000 mm | 1.738 mm | 2.081 mm | 1.919 mm |
| 1.5 mm | 3.393 mm | 3.000 mm | 2.607 mm | 3.122 mm | 2.878 mm |
| 2 mm | 4.524 mm | 4.000 mm | 3.476 mm | 4.163 mm | 3.837 mm |
| 3 mm | 6.786 mm | 6.000 mm | 5.214 mm | 6.244 mm | 5.756 mm |
| 4 mm | 9.048 mm | 8.000 mm | 6.952 mm | 8.325 mm | 7.675 mm |
| 5 mm | 11.310 mm | 10.000 mm | 8.690 mm | 10.407 mm | 9.593 mm |
| 6 mm | 13.572 mm | 12.000 mm | 10.428 mm | 12.488 mm | 11.512 mm |
The K-factor choice moves a 2 mm part by 0.36 mm per bend in that bend allowance calculator chart. On a box with four bends, that adds up to 1.4 mm in the flat, which is why the K source matters more than the formula.
Gauge sizes are not round decimals, so look up the real thickness before any bend allowance calculator for sheet metal. The Sheet Metal Gauge Calculator converts 16 gauge steel to 0.0598 in before any bend math.
K-Factor From DIN 6935 vs Real Shop Bends
DIN 6935 puts K at 0.325 when the inside radius equals the thickness and 0.500 once R/T reaches 5. Air-bent steel and aluminum often land higher at tight radii, so a DIN-based bend allowance calculator result can overstate the bend deduction.
R is the inside bend radius and T is the thickness. The DIN 6935 correction factor k is 0.65 + 0.5 log(R/T) below an R/T of 5 and 1 above it, and the K-factor is half of k.
| R/T | 0.25 | 0.5 | 1 | 1.5 | 2 | 3 | 4 | 5+ |
|---|---|---|---|---|---|---|---|---|
| DIN 6935 K | 0.174 | 0.250 | 0.325 | 0.369 | 0.400 | 0.444 | 0.476 | 0.500 |
SendCutSend publishes measured K-factors and 90° deductions for its own press brakes. Running their K through the same bend allowance calculator math reproduces their deductions within 0.0035 in, which confirms the formula.
| Material | Thickness | Radius | R/T | Shop K | BD at Shop K | Published BD | DIN K | BD at DIN K |
|---|---|---|---|---|---|---|---|---|
| Mild steel | 0.059 in | 0.063 in | 1.07 | 0.40 | 0.1080 in | 0.108 in | 0.332 | 0.1143 in |
| Mild steel | 0.119 in | 0.063 in | 0.53 | 0.38 | 0.1940 in | 0.1955 in | 0.256 | 0.2172 in |
| Mild steel | 0.250 in | 0.150 in | 0.60 | 0.36 | 0.4230 in | 0.4215 in | 0.270 | 0.4585 in |
| 304 stainless | 0.060 in | 0.070 in | 1.17 | 0.34 | 0.1180 in | 0.1185 in | 0.342 | 0.1178 in |
| 5052 aluminum | 0.063 in | 0.035 in | 0.56 | 0.42 | 0.0995 in | 0.096 in | 0.261 | 0.1152 in |
| 5052 aluminum | 0.125 in | 0.125 in | 1.00 | 0.44 | 0.2173 in | 0.216 in | 0.325 | 0.2398 in |
| Copper | 0.125 in | 0.050 in | 0.40 | 0.34 | 0.2047 in | 0.205 in | 0.226 | 0.2272 in |
DIN K is close for stainless at an R/T near 1, within 0.0007 in of the published deduction. Below an R/T of about 0.6 it runs 0.09 to 0.16 lower than the shop value, which overstates the deduction by 0.036 in on 1/4 in steel.
That gap is a case where a textbook K leads a steel bend allowance calculator to the wrong blank. Use the DIN value as a starting point for a new material, then switch to a K backed out of a test bend for production parts.
The DIN formula also breaks down at near-sharp bends. Below an R/T of 0.05 it returns a K of zero or less, which would put the neutral axis inside the metal's inner face, so use a measured K for sharp air bends instead.
Outside Setback, Deduction and the Flat Blank
Bend deduction is twice the outside setback minus the bend allowance. For the 0.060 in sheet with a 0.060 in radius, that is 2 × 0.1200 - 0.1357 = 0.1043 in.
A is the bend angle in degrees, R the inside radius, K the K-factor and T the thickness. The term R + K × T is the neutral axis radius, 0.0864 in in the example, where the metal neither stretches nor shrinks.
The outside setback OSSB runs from the tangent line to the virtual sharp, the point where both outside faces would meet. At 90° it is simply R + T, or 0.1200 in in the example.
Both methods land on the same blank, which makes them a quick check on any bend allowance calculator result.
Outside flanges of 3 in and 2 in minus a 0.1043 in deduction give 4.8957 in, and flat legs of 2.8800 in and 1.8800 in plus the 0.1357 in allowance give the same 4.8957 in.
The flange reference changes the bend allowance calculator blank more than any K choice. The same 3 in and 2 in flanges give 4.8957 in if measured outside, 5.0157 in if measured to the inside mold line and 5.1357 in if they are already flat legs.
| Flanges Measured To | Setback Removed per Flange | Flat Blank |
|---|---|---|
| Outside mold line | 0.1200 in | 4.8957 in |
| Inside mold line | 0.0600 in | 5.0157 in |
| Tangent (flat legs) | 0 | 5.1357 in |
Mark the bend line at the middle of the bend zone found by the bend allowance calculator math. For the example it sits 2.9479 in from the edge of the 3 in flange and 1.9479 in from the other edge, which sets the backgauge on the press brake.
Without a K-Factor, From One Test Bend
With no K-factor on hand, work backward from one test strip of known flat length, its two outside flanges and its angle.
For a bend allowance calculator without K factor data, a 4.896 in strip bent to 3 in and 2 in outside flanges in 0.060 in sheet with a 0.060 in radius gives K = 0.443.
L1 and L2 are the measured outside flanges and Lf the flat strip length. The deduction is 3 + 2 - 4.896 = 0.104 in, the allowance is 2 × 0.1200 - 0.104 = 0.136 in, and dividing by the 1.5708 radian angle sets the neutral axis.
Small measuring errors swing K a lot on thin sheet. A flat strip of 4.890 in instead of 4.896 in gives K 0.379, and 4.900 in gives K 0.485, so a 0.006 in caliper error moves K by about 0.06.
| Test Strip | Measured Flanges | Bend Deduction | Bend Allowance | K-Factor |
|---|---|---|---|---|
| 0.060 in sheet, 4.890 in flat | 3 in + 2 in | 0.1100 in | 0.1300 in | 0.379 |
| 0.060 in sheet, 4.896 in flat | 3 in + 2 in | 0.1040 in | 0.1360 in | 0.443 |
| 0.060 in sheet, 4.900 in flat | 3 in + 2 in | 0.1000 in | 0.1400 in | 0.485 |
| 2 mm sheet, 96.5 mm flat | 50 mm + 50 mm | 3.500 mm | 4.500 mm | 0.432 |
The K error equals the length error divided by the angle in radians times the thickness. The same 0.006 in error moves K by 0.064 on 0.060 in sheet but only 0.015 on 0.250 in plate, so thin stock needs a micrometer.
Real K-factors for sheet bends sit between about 0.25 and 0.50. A test-bend result outside that range almost always means a mis-measured flange or angle rather than unusual metal.
The K-Factor Calculator breaks the same test bend into its Y-factor and neutral axis, ready for the next bend allowance calculator run on that material.
Included Angle vs Bend Angle
The bend angle is how far the sheet turns from flat, and the included angle is what remains between the flanges. A 45° bend and a 45° included angle are different parts, and mixing them changes the blank by 0.344 in on 3 in and 2 in flanges.
| Bend Angle | Included Angle | Bend Allowance | Outside Setback | Bend Deduction |
|---|---|---|---|---|
| 15° | 165° | 0.0226 in | 0.0158 in | 0.0090 in |
| 30° | 150° | 0.0452 in | 0.0322 in | 0.0191 in |
| 45° | 135° | 0.0679 in | 0.0497 in | 0.0316 in |
| 60° | 120° | 0.0905 in | 0.0693 in | 0.0481 in |
| 90° | 90° | 0.1357 in | 0.1200 in | 0.1043 in |
| 120° | 60° | 0.1810 in | 0.2078 in | 0.2347 in |
| 135° | 45° | 0.2036 in | 0.2897 in | 0.3758 in |
| 150° | 30° | 0.2262 in | 0.4478 in | 0.6695 in |
That 90 degree bend allowance chart and the rest of the angles use 0.060 in sheet, a 0.060 in radius and K 0.44. Bend allowance grows in a straight line with angle, but the outside setback follows tan(A/2), so the deduction climbs fast past 90°.
At 150° the deduction is 0.6695 in, more than six times the 90° figure. Outside flanges on bends past 90° are measured to the virtual sharp, which sits well beyond the metal, so check drawings dimensioned to the actual edge.
A 90 degree bend calculation is the one case where both angles agree. Drawings, CAD and press brakes do not share one convention, so confirm which angle a drawing gives before any bend allowance calculator result reaches the cut list.
Round Bar, Tube and Pipe at K 0.5
A round bar or tube bends about its centerline, so any bend allowance calculator for round bar should use K 0.5. A 1 in tube with a 2.5 in inside radius, or a 3 in centerline radius, uses 4.7124 in for a 90° bend.
| Bar or Tube OD | Inside Radius | Centerline Radius | 90° Bend Allowance | Outside Setback | Bend Deduction |
|---|---|---|---|---|---|
| 0.5 in | 1.5 in | 1.75 in | 2.7489 in | 2.0000 in | 1.2511 in |
| 1 in | 2.5 in | 3 in | 4.7124 in | 3.5000 in | 2.2876 in |
| 1 in | 4.5 in | 5 in | 7.8540 in | 5.5000 in | 3.1460 in |
| 1.5 in | 3.75 in | 4.5 in | 7.0686 in | 5.2500 in | 3.4314 in |
| 2.375 in (2 in pipe) | 6 in | 7.1875 in | 11.2901 in | 8.3750 in | 5.4599 in |
Here the thickness term is the outside diameter, so the setback runs to the outside of the tube. A 25 mm tube on a 75 mm centerline radius uses 117.81 mm at 90° and 58.90 mm at 45°.
Tube benders list the die by centerline radius, so subtract half the OD to get the inside radius for a bend allowance calculator for tubing.
Springback and wall thinning are not part of the arc length, and the die maker's chart sets how far past the target to bend.
Allowance, Deduction and Bending Calculators Explained
Each answer below uses the bend allowance calculator example of 0.060 in sheet, 0.060 in radius and K 0.44 example unless another part is named. Different K sources or flange references move the blank by the amounts shown above.
What is bend allowance?
Bend allowance is the length of the neutral axis through a bend, the part of the flat blank that becomes the curve. For a 90° bend in 0.060 in sheet with a 0.060 in radius at K 0.44, it is 0.1357 in.
To find a bend allowance, multiply the bend angle in radians by the neutral axis radius, R + K × T. Here that is 1.5708 × 0.0864 = 0.1357 in, and adding it to the two flat legs gives the bend allowance calculator blank length.
What are bend allowance and bend deduction calculations?
They are two ways to reach the same flat blank. Bend allowance adds the bend's arc to the flat legs, while bend deduction subtracts a fixed amount from the outside flange lengths, 0.1043 in for the example bend.
A bend deduction calculator suits drawings dimensioned to the outside, since 3 + 2 - 0.1043 gives 4.8957 in at once. Allowance suits CAD and parts dimensioned to the tangent lines, and both stay linked by BD = 2 × OSSB - BA.
What is a sheet metal bending calculator?
A sheet metal bending calculator turns thickness, inside radius, angle and K-factor into the flat blank and bend line positions. For the example part, that means a 4.8957 in blank with the bend line at 2.9479 in.
Results depend on the K input above all. On 2 mm sheet a K of 0.44 instead of the DIN 0.325 shifts each 90° bend by 0.36 mm, so a sheet metal bend allowance calculator is only as good as the K-factor behind it.